SOLIDWORKS Split Line: How It Works and When to Use It

How-to basics · Updated November 22, 2026

In SOLIDWORKS, Split Line divides one or more model faces into smaller selectable faces by creating edges on them; it does not remove material or separate a part into multiple bodies. To use it, choose Insert > Curve > Split Line, select a method such as Projection, Silhouette, or Intersection, then specify the geometry and faces that define the split.

What the Split Line feature does

A Split Line adds boundary edges to existing faces. Those edges partition the face into regions that SOLIDWORKS can treat as separate faces for later selections and operations. The underlying solid remains the same shape unless you add another feature that changes it. For example, splitting a curved housing face does not create a groove: it creates an edge on the surface, with a face region on either side.

This is useful because many modeling tasks depend on face boundaries. You can select one of the new regions to apply a different appearance, define a boundary for a downstream feature, or identify an area for further modeling. Split Line is also commonly used to define a visible parting line on a molded component. The line itself is model geometry, not merely a sketch drawn over the rendered image.

It is important to distinguish a split face from a split body. A Split Line divides faces on a body but does not, by itself, create separate solid bodies. SOLIDWORKS also has a Split feature, used to divide a part into separate bodies and potentially save those bodies as separate part files. The similarly named tools solve different problems.

How the three methods work

The Split Line PropertyManager provides three methods. The method determines how SOLIDWORKS calculates the boundary, so choose it according to the geometry you have rather than treating the options as interchangeable.

  • Projection: Projects a sketch onto selected model faces to create split edges where the projected sketch meets them. This is a good choice when you can draw the desired boundary in a plane, such as a curve that should cross a curved enclosure.
  • Silhouette: Creates a split along the silhouette, or apparent outline, of selected faces as viewed from a specified direction. It is useful when the boundary should follow the visible contour of a shape from a chosen viewing direction, including some parting-line workflows.
  • Intersection: Creates a split where selected model faces intersect a selected plane, surface, or face. Use it when the boundary is naturally defined by another piece of geometry, rather than by a projected sketch.

All three methods create face boundaries; none is a substitute for a cut when material must be removed. A projected curve can appear differently on a curved face than it does in its original sketch plane because the software maps the curve onto the model surface. The preview is therefore worth checking before accepting the feature.

Creating a Split Line from a sketch

For a typical projection, start with a sketch that describes the boundary and a solid or surface face to receive it. The sketch may be on a plane that intersects or faces the target area; it does not have to lie directly on the curved face. The exact selections and available controls can vary with the selected method and SOLIDWORKS version, but this general sequence is a reliable starting point:

  1. Create or identify a sketch containing the desired curve. Make sure the sketch is visible and that its position and orientation allow it to project onto the intended faces.
  2. Choose Insert > Curve > Split Line. If the menu is inconvenient to reach, SOLIDWORKS Command Search can locate the command by its name.
  3. In the PropertyManager, choose Projection. Select the sketch as the projecting geometry, then select the model face or faces to split in the appropriate selection box.
  4. Inspect the preview. Confirm that the projected boundary reaches the intended faces and does not create extra splits on faces you did not mean to include.
  5. Accept the feature, then inspect the new face regions and edges. If the result is wrong, edit the feature or its source sketch rather than drawing over the unwanted edge.

For example, suppose a plastic cover has a domed top and needs a colored band that follows a wavy boundary. Draw the wave in a suitable plane, use Projection, and select the dome face. The projected curve divides the dome into selectable regions, allowing separate appearances. The operation does not form a physical step or recess; a separate modeling feature would be needed for that.

Choosing the right method

Think about what defines the boundary. If you can draw it as a curve and project that curve onto faces, Projection is usually the most direct route. If the boundary should be the outline of the part from a particular direction, consider Silhouette. If a plane or surface already crosses the target and its intersection is the boundary you need, choose Intersection.

Here are practical examples:

  • Use Projection to mark a logo outline or a color boundary on a curved face, provided the sketch can project cleanly onto that area.
  • Use Silhouette when you need a contour based on the shape as seen from a defined direction, rather than a hand-drawn curve.
  • Use Intersection to divide a face at the location where a reference plane or surface crosses it, such as a boundary aligned to a tooling surface.

Complex geometry may make more than one method possible. In that case, prefer the method whose inputs best express the design intent. A sketch-driven boundary is often easiest to adjust by editing its dimensions or relations. An intersection-driven boundary can be more robust when it must stay tied to a controlling plane or surface. A silhouette boundary depends on the chosen viewing direction, so make that direction an intentional part of the feature setup.

Common reasons to use it

Split Line is often used for appearance control. After the split, select a face region and use the appearance controls to assign a color or finish to that region. This is different from adding a decal: an appearance changes the rendering of a face, while a decal places an image on a surface. A split can define a clean region for an appearance, but it does not create printed artwork or physical texture by itself.

It can also help with manufacturing-oriented models. A designer may add a parting line to communicate where mold halves meet, or divide a surface into areas that need separate attention in later modeling. The feature can make regions easier to select, but it does not automatically calculate mold tooling, prove that a part can be released from a mold, or validate a manufacturing process. Those tasks require additional design work and appropriate checks.

Another useful role is organizing selections for later features. A boundary can give you a distinct face region to use as a reference or target. However, downstream features can depend on the generated faces and edges. If you later alter the sketch or the target surface, those references may change, so review dependent features after substantial edits.

Split Line compared with related tools

A common misconception is that Split Line cuts the part. It does not make a slot, groove, or opening. For a physical cut, use a suitable material-removing feature such as Cut-Extrude or Cut-Sweep. If you only need a boundary on a surface, Split Line avoids changing the part’s volume.

It is also different from Split. Use Split Line when one face needs to become multiple face regions on the same body. Use Split when the goal is to divide a part into separate bodies, for example as part of a multibody workflow. And if the goal is to draw a visible curve without changing face topology, a sketch may be enough, though a sketch alone does not create separate selectable face regions for appearance assignment.

For cosmetic markings, a decal may be more suitable than a split if the artwork is an image and does not need to define model face boundaries. For a real groove, emboss, or raised edge, use a feature that adds or removes material. Selecting the simplest tool that matches the intended result helps keep the model tree understandable.

Common problems and how to fix them

If the feature fails or the preview is incomplete, first check whether the sketch or intersecting geometry actually reaches the target faces. A curve that stops short, lies on the wrong side, or misses part of a curved face may not produce the boundary you expect. Verify the geometry in a view that makes the projection direction and target faces clear.

  • No split appears: Confirm that you selected the intended faces, and that the sketch or intersecting surface crosses them. Check that the sketch is visible and that the selected Split Line method matches the geometry.
  • Extra faces are split: Narrow the target-face selection. Selecting a whole body or many neighboring faces can create more boundaries than intended.
  • The curve lands on the wrong side: Review the sketch plane and projection direction. Reorient the sketch or adjust the direction controls available in the PropertyManager.
  • The feature becomes fragile after edits: Check whether later features reference edges or face regions that changed when the split was revised. Repair or redefine those references in the feature tree.
  • The result looks like a cut but is not one: The edge may be visible, but the volume has not changed. Use a cut or other shape-changing feature if the design requires depth.

For difficult models, try the feature on a simpler copy or suppress unrelated features temporarily to isolate the issue. A small, clear sketch and a limited set of target faces are easier to diagnose than a large sketch projected onto an entire complex body. Once the split works, restore the other features and check for rebuild errors.

Modeling tips for stable results

Keep the feature tied to meaningful design references. If the split represents a required band width or parting location, dimension the sketch or locate its supporting plane from stable model geometry. Avoid relying on an arbitrary screen position or a temporary edge if a datum plane, axis, or dimension can express the intent more clearly.

Use descriptive names for the sketch and Split Line feature in the FeatureManager design tree, especially when the model contains several regions for different finishes. This makes later edits easier to understand. After changing the source sketch, rebuild the model and inspect all downstream features, appearances, and drawings that rely on the divided faces.

Finally, check the result at the level that matters. For visual presentation, inspect the assigned appearance and rendered boundary. For a drawing or manufacturing handoff, confirm that the edge is represented as intended and that the model does not imply a groove where none exists. A Split Line is useful precisely because it separates regions without changing shape, but that distinction should be clear to anyone who uses the model.

Frequently Asked Questions

Does a SOLIDWORKS Split Line remove material?
No. It divides faces by adding edges and creating separate face regions. To remove material, create a cut feature such as Cut-Extrude.

Can Split Line be used on a curved surface?
Yes. Projection can map sketch geometry onto selected curved faces, while Silhouette and Intersection define boundaries in other ways. Check the preview because the resulting curve follows the target geometry, not necessarily the sketch’s flat appearance.

Why can I not select the new area separately?
Check that the Split Line feature completed successfully and that the boundary actually divides the face. If you need a separate selectable face region, a visible sketch curve alone is not the same as a successful face split.

What is the difference between Split Line and Split?
Split Line divides faces on a body and leaves the body intact. Split is used to divide a part into separate bodies, so use it when the model needs multiple bodies rather than additional face boundaries.

Can I use a Split Line to apply two colors to one surface?
Yes. Create the boundary so it divides the surface into separate face regions, then assign appearances to those regions. The split defines the areas; it does not apply colors automatically.

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